Skip to content

Latest commit

 

History

History
209 lines (177 loc) · 6.92 KB

README.md

File metadata and controls

209 lines (177 loc) · 6.92 KB
Raw

Build Status PyPI

Routines for generating and parsing KiCAD files

There are multiple python scripts that read and write kicad file formats. Currently there is the problem that each project reimplements basic parsing and serialization of these formats.

The aim of this project is to provide high quality and well tested format support so that other projects can focus on the interesting stuff.

Status

Complete support for the kicad_pcb and kicad_mod formats. The schemas of the classes should provide good documentation on the kicad file format. A summary of all methods and fields can be found in the section API docs.

Usage

from numpy import array
from pykicad.pcb import *
from pykicad.module import *

# Define nets
vi, vo, gnd = Net('VI'), Net('VO'), Net('GND')

# Load footprints
r1 = Module.from_library('Resistors_SMD', 'R_0805')
r2 = Module.from_library('Resistors_SMD', 'R_0805')

# Connect pads
r1.pads[0].net = vi
r1.pads[1].net = vo
r2.pads[0].net = vo
r2.pads[1].net = gnd

# Place components
r1.at = [0, 0]
r2.at = [5, 0]

# Compute positions
start = array(r1.pads[1].at) + array(r1.at)
end = array(r2.pads[0].at) + array(r2.at)
pos = start + (end - start) / 2

# Create vias
v1 = Via(at=pos.tolist(), size=.8, drill=.6, net=vo.code)

# Create segments
s1 = Segment(start=start.tolist(), end=pos.tolist(), net=vo.code)
s2 = Segment(start=pos.tolist(), end=end.tolist(), net=vo.code)

# Create zones
coords = [(0, 0), (10, 0), (10, 10), (0, 10)]
gndplane_top = Zone(net_name='GND', layer='F.Cu', polygon=coords, clearance=0.3)


layers = [
    Layer('F.Cu'),
    Layer('Inner1.Cu'),
    Layer('Inner2.Cu'),
    Layer('B.Cu'),
    Layer('Edge.Cuts', type='user')
]

for layer in ['Mask', 'Paste', 'SilkS', 'CrtYd', 'Fab']:
    for side in ['B', 'F']:
        layers.append(Layer('%s.%s' % (side, layer), type='user'))

nc1 = NetClass('default', trace_width=1, nets=['VI', 'VO', 'GND'])

# Create PCB
pcb = Pcb()
pcb.title = 'A title'
pcb.comment1 = 'Comment 1'
pcb.page_type = [20, 20]
pcb.num_nets = 5
pcb.setup = Setup(grid_origin=[10, 10])
pcb.layers = layers
pcb.modules += [r1, r2]
pcb.net_classes += [nc1]
pcb.nets += [vi, vo, gnd]
pcb.segments += [s1, s2]
pcb.vias += [v1]
pcb.zones += [gndplane_top]

pcb.to_file('project')

Supported file formats

  • Modules (*.pretty, *.kicad_mod) in module.py
  • Pcbnew (*.kicad_pcb) in pcb.py

API docs

modules.py

Classes

  • Module(name, version, locked, placed, layer, tedit, tstamp, at, descr, tags, path, attr, autoplace_cost90, autoplace_cost180, solder_mask_margin, solder_paste_margin, solder_paste_ratio, clearance, zone_connect, thermal_width, thermal_gap, texts, lines, circles, arcs, curves, polygons, pads, models)
    • pads_by_name(name)
    • set_reference(name)
    • set_value(value)
    • geometry()
    • elements_by_layer(layer)
    • courtyard()
    • place(x, y)
    • rotate(angle)
    • connect(pad, net)
    • flip()
    • from_file(cls, path)
    • from_library(cls, lib, name)
  • Pad(name, type, shape, size, at, rect_delta, roundrect_rratio, drill, layers, net, die_length, solder_mask_margin, solder_paste_margin, solder_paste_margin_ratio, clearance, zone_connect)
    • rotate(angle)
    • flip()
  • Drill(size, offset)
  • Net(code, name)
  • Model(path, at, scale, rotate)
  • Text(type, text, at, layer, size, thickness, bold, italic, justify, hide, tstamp)
    • rotate(angle)
    • flip()
  • Line(start, end, layer, width, tstamp, status)
    • flip()
  • Circle(center, end, layer, width, tstamp, status)
    • flip()
  • Arc(start, end, angle, layer, width, tstamp, status)
    • flip()
  • Polygon(pts, layer, width, tstamp, status)
    • flip()
  • Curve(start, bezier1, bezier2, end, layer, width, tstamp, status)
    • flip()

pcb.py

Classes

  • Pcb(version, host, board_thickness, num_nets, num_no_connects, title, date, rev, company, comment1, comment2, comment3, comment4, page_type, portrait, setup, layers, nets, net_classes, modules, segments, vias, texts, lines, arcs, circles, polygons, curves, zones, targets, dimensions)
    • geometry()
    • elements_by_layer(layer)
    • outline()
    • module_by_reference(name)
    • net_by_code(code)
    • to_file(path)
    • from_file(cls, path)
  • Segment(start, end, net, width, layer, tstamp, status)
  • Text(text, at, layer, size, thickness, bold, italic, justify, hide, tstamp)
  • Line(start, end, width, layer, tstamp, status)
  • Arc(start, end, angle, layer, width)
  • Circle(center, end, layer, width, tstamp, status)
  • Polygon(pts, layer, width, tstamp, status)
  • Curve(start, bezier1, bezier2, end, layer, width, tstamp, status)
  • Via(micro, blind, at, size, drill, layers, net, tstamp, status)
  • Layer(code, name, type, hide)
  • NetClass(name, description, clearance, trace_width, via_dia, via_drill, uvia_dia, uvia_drill, diff_pair_width, diff_pair_gap, nets)
  • Zone(net, net_name, layer, tstamp, hatch_type, hatch_size, priority, connect_pads, clearance, min_thickness, fill, fill_mode, arc_segments, thermal_gap, thermal_bridge_width, smoothing, radius, keepout_tracks, keepout_vias, keepout_copperpour, polygon, filled_polygon, fill_segments)
  • Target(shape, at, size, width, layer, tstamp)
  • Dimension(value, width, layer, text, feature1, feature2, crossbar, arrow1a, arrow1b, arrow2a, arrow2b, tstamp)
  • Setup(user_trace_width, trace_clearance, zone_clearance, zone_45_only, trace_min, segment_width, edge_width, via_size, uvia_size, uvia_drill, uvias_allowed, blind_buried_vias_allowed, uvia_min_size, uvai_min_drill, pcb_text_width, pcb_text_size, mod_edge_width, mod_text_size, mod_text_width, pad_size, pad_drill, pad_to_mask_clearance, solder_mask_min_width, pad_to_paste_clearance, solder_to_paste_clearance_ratio, grid_origin, visible_elements, pcbplotparams)

Functions

  • find_library(library)
  • find_module(library, module)
  • list_libraries()
  • list_modules(library)
  • list_all_modules()
  • filter_by_regex()
  • flip_layer()

Global variables

  • MODULE_SEARCH_PATH

Project using pykicad

License

ISC License

Copyright (c) 2017, David Craven

Permission to use, copy, modify, and/or distribute this software for any purpose with or without fee is hereby granted, provided that the above copyright notice and this permission notice appear in all copies.

THE SOFTWARE IS PROVIDED "AS IS" AND THE AUTHOR DISCLAIMS ALL WARRANTIES WITH REGARD TO THIS SOFTWARE INCLUDING ALL IMPLIED WARRANTIES OF MERCHANTABILITY AND FITNESS. IN NO EVENT SHALL THE AUTHOR BE LIABLE FOR ANY SPECIAL, DIRECT, INDIRECT, OR CONSEQUENTIAL DAMAGES OR ANY DAMAGES WHATSOEVER RESULTING FROM LOSS OF USE, DATA OR PROFITS, WHETHER IN AN ACTION OF CONTRACT, NEGLIGENCE OR OTHER TORTIOUS ACTION, ARISING OUT OF OR IN CONNECTION WITH THE USE OR PERFORMANCE OF THIS SOFTWARE.